Finish Planing / Radiusing a Fingerboard Billet

The goal of the finishing cut is to create a surface that is smooth and free from cutting artifacts. At this stage in the process, it is very likely that all of the inlay (if any) has been installed and the fret-slots are cut and ready for wire insertion. With careful selelction of the stepover and chipload (depending on the billet material) a surface can be cut that is smooth enough to see the reflection of the bit (see attached video)

As with the roughing pass considered earlier, the tool of choice will be a 3-flute planing / radiusing cutter designed specifically to cut finished surfaces that, in many cases, do not need sanding or polishing.

To proceed with the finishing cut:

• Calculate the feed rate using a TOTAL chipload of 0.0079" (0.200 mm).
• • To determine your feed-rate, simply multiply the total chipload by the RPM of your spindle.
  • 
    
  • For example, if your spindle is turning 24,000 RPM, use a feed rate of 24,000 X 0.0079" (0.20 mm) = 190 IPM (inches per minute) (4.8 M/min).
  • 
    
  • In no case should you use a total chipload less than 0.006" (0.15 mm) because you may be operating very near the "burn point" where too much heat is being generated and not enough is being carried away by the chips being ejected from the cut.
• 
  
• set the cut depth to the desired position of the finished surface
• Set the step-over to 0.017" (0.44 mm)
• Enter the RPM, calculated feed-rate and stepover into the CAM software (usually in the tool library) and generate the finishing toolpath.
• Load the toolpath into the CNC controller.
• Set the Z=0 point about 1" (25mm) above the billet and run the code in the air to make sure there are no mistakes or surprises.
• 
  
• An "air pass" is a VERY good idea if you are working with a billet with expensive inlay already installed (or if you have finally come to the realization that your time is actually worth something)!.
• 
  
• Things to watch for include:
• • Make sure that the spindle turns on and is turning in the right direction at the specified RPM.
  • Insure that toolpath stays within the edges of the billet, avoids any clamps or hold-downs and does not include any unexpected moves.
  • Check that the tool returns to the specified HOME position and shuts off the spindle when the air-cut is finished.
• 
  
• Find a convenient spot on the billet to set the Z=0 (Z-zero) position on the top surface of the billet..
• Retract tool to a safe distance.
• You should now be ready to run the code and cut the finishing pass

Finish radiusing a fingerboard